Say I have a 3 sheet drawing with 4 views on each sheet and a BOM on each  sheet. I know that I can go into the view properties and set the view to be related to a particular BOM. I know that when a BOM of a configuration is created the Quantity can reference which configuration in the header.

               BUT

     To date I have not been able to determine which view the BOM was created from. We typically set our BOMs to not show which configuration it came from, or if the config is referenced we go into the header and delete the information. If nothing else the BOM is 6 to 10 spaces narrower. However if I now open a 10 year old drawing and start working on it there may be times that I need to know which of the 4 views it came from and I have no idea how to do that.

 

     Can someone help me?


Categories: Drawings and Detailing

Comments
Last comment By: Jim Steinmeyer   Mon, 14 Jan 2019 15:13:56 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

The only way I know of is not a great way but it works as long as you haven't changed the option already. By default any view other than the one the BOM was originally linked to will NOT have the "Link balloon text to specified table" option selected. So if you have not changed that in the other views you can tell by process of elimination.

 

However, if you have multiple BOM's in a drawing you have probably already set this option in order to avoid your drawing becoming a balloon orphanage.

By: Joel Gilbert  Fri, 11 Jan 2019 22:47:08 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

It seems like it should show the view when you select the BOM with the dashed lines like when you hover the mouse over a view to add an annotation or something.  This seems it would be very easy for the SW people to fix.

By: Matt Peneguy  Fri, 11 Jan 2019 22:51:47 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

That is correct. Especially with drawings that have been around for years and the assembly has now been revised.

I could delete the BOM and create a new one but surely there must be a better way.

By: Jim Steinmeyer  Fri, 11 Jan 2019 22:54:02 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

I found it strange you stating that you set your BOM not to show which configuration they were made from, the configuration is still in the table definition and can be retrieved by going to the BOM property manager.

 

That aside, there is not a way to tell which view a BOM was made from anymore (excel based BOMs you were at one time but I have not used those since the inception of the SW BOMs).  You could check what views use the same configuration that the BOM was made from to get an idea but since views are not linked to the BOM, you could create a BOM from a view then change the configuration that view uses and you would never know.

 

In fact once you create a BOM, you can delete the view and the BOM does not care.  Bottom line the view is only used to get the model the BOM uses.

 

EDIT:  Can you expand on why you need to know which view the BOM was created from?

By: Solid Air  Fri, 11 Jan 2019 23:28:38 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

Jim, I'm not on Solidworks at the moment, but if I seem to remember that when you click in the BOM cell, the part is highlighted in the view.

By: Sergio Monti  Sat, 12 Jan 2019 00:22:02 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

That might help, maybe. I will check it tomorrow.

Thank you

By: Jim Steinmeyer  Mon, 14 Jan 2019 01:05:39 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

Solid Air wrote:

 

 

EDIT: Can you expand on why you need to know which view the BOM was created from?

     I am working on an old assembly / drawing where over time the company has placed the hardware in bolt bags per our MRP system, but have never caught the assembly or drawing up to the new standard. I am now placing a different motor in the assembly and would like to correct everything else at the same time.

     There are several views and a couple of BOMs on the drawing and there are also several configurations in the assembly. Sometimes, since we build machinery that may have the same (relatively) subassembly in several assemblies, there are configurations for completely different drawings of different assemblies. Are we confused yet? I am.

     Anyway as I go through the process of taking the hardware and placing it in virtual subassemblies some of my views and balloons are not behaving as I thought I thought they should. So I was wanting to determine which view the main BOM came from since it does not appear to be View 1.

By: Jim Steinmeyer  Mon, 14 Jan 2019 01:15:35 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

As I stated in my previous post, SolidWorks Bill of Material are view independent.  The view used only sets the assembly model the BOM is created from.  Best you can do is compare the configuration the BOM uses to the configuration a view uses.  If they are the same and the balloons do not match then you need to start looking at parts excluded from BOM, components that have changed and configuration properties of the sub assemblies (set to hide, show or promote).  And yes I am confused especially since I cannot see the issue first hand.

By: Solid Air  Mon, 14 Jan 2019 01:45:27 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

Thank you. Knowing that they are totally independent once created would answer why I am not finding any tags. It may simply be better to delete and recreate except I am also playing with making an indented BOM and then collapsing everything other than the bolt bags and then right justifying those components to signify that they are part of a subassembly. We will see what turns out.

By: Jim Steinmeyer  Mon, 14 Jan 2019 14:34:46 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

Sergio Monti wrote:

 

Jim, I'm not on Solidworks at the moment, but if I seem to remember that when you click in the BOM cell, the part is highlighted in the view.

Just tried selecting a couple of the larger components in the BOM and they did not highlite in any of the drawing views.

By: Jim Steinmeyer  Mon, 14 Jan 2019 14:38:57 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

The part is highlighted in all views, 2018SP5.

BOM-01.jpg

By: Frederick Law  Mon, 14 Jan 2019 14:39:46 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

Hey Jim,

 

I need to pull the Left Bar of the BOM if I want them to highlight themselves. This might have to do with the version I use

 

By: Alex Lachance  Mon, 14 Jan 2019 14:44:40 GMT
Re: Is there a way to tell which drawing view a BOM is based on?

Like my other post on BOMs this has really been a collaborative effort to get the answer I was looking for but I gave the correct answer to Solid Air. Like he indicated I can double click on the header for the QTY column of the BOM to determine which config it comes from. Then I can select a view and see which config it references to draw the conclusion which view will relate best to the BOM.

My problem in this case appears to be that the BOM was not generated off the default config and thus did not have all of the desired components in it. Then when I went to balloon components in other views I found some that just gave me the star rather than a number like I knew they should have. Now that I have the knowledge of the BOM's config I can set it to the one I need.

     Thank you all for your help.

By: Jim Steinmeyer  Mon, 14 Jan 2019 15:13:56 GMT
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