Hello,

I have a part in my design library that I would like to be able to drag and drop non-linked copies of into my assembly. The idea is that my library part has undefined dimensions, and when I drop it in I can then define the dimensions to my assembly without changing the original as there will be multiple variations of the same part. I understand there are ways to do this with pack and go and what not but I am looking to do this easily. I am using 2016.

 

Thanks


Categories: Modeling and Assemblies, Assemblies

Comments
Last comment By: Jim Steinmeyer   Fri, 21 Apr 2017 15:47:53 GMT
Re: How to drag an un-linked part copy from design library?

Hi Joel,

 

there are several ways to do this (without claiming that these are all):

  1. You could use "Make independent":

    You will be asked to save the component to a different location.

  2. You could convert the part to become a virtual component:

    Creating a virtual component will break the link to the original part and later on you could save it to your desired location.

  3. You could open the part in a separate window and make a save as:

    You will get different options whether the newly created part will be used as the new reference or not.

Hope this helps.

Kind regards

Frank

SOLIDWORKS Product Definition Team

By: Frank Ruepp  Fri, 21 Apr 2017 14:18:41 GMT
Re: How to drag an un-linked part copy from design library?

Frank,

I think this is related so maybe you can clear this up for me. Like Joel I have part profiles (the profile of a structural I-beam for example) that I will drag from the design library and place as a new part and I am asked if I want a Derived part or not. As a rule I desire to make this part unlinked to the original and save it as a new part number. Commonly the library part is stored as a 12" long part and I want to save it at a different length and give it a new part number and description saving the material information.

     What is the difference between derived or not?

By: Jim Steinmeyer  Fri, 21 Apr 2017 14:57:43 GMT
Re: How to drag an un-linked part copy from design library?

Thanks Frank,

 

I found that 'make independent' shortly after I posted. That seems to be my best option. I was really hoping that  there was a keyboard modifier I was missing to be able to do this from dragging from the library, but it guess it doesn't exist. Maybe a future feature?

 

Thanks again,

By: Joel Murphy  Fri, 21 Apr 2017 14:24:31 GMT
Re: How to drag an un-linked part copy from design library?

Hi Jim,

 

are you talking about this message:

 

Kind regards

Frank

SOLIDWORKS Product Definition Team

By: Frank Ruepp  Fri, 21 Apr 2017 15:12:06 GMT
Re: How to drag an un-linked part copy from design library?

Yes, that is the one.

By: Jim Steinmeyer  Fri, 21 Apr 2017 15:19:21 GMT
Re: How to drag an un-linked part copy from design library?

Hi Joel,

 

I like the idea of having i.e. a "CTRL" + Drag feature that would automatically open up the save as dialog.

 

Kind regards

Frank

SOLIDWORKS Product Definition Team

By: Frank Ruepp  Fri, 21 Apr 2017 15:21:00 GMT
Re: How to drag an un-linked part copy from design library?

Hi Jim,

 

you will always get this message when you drag a part into another part.  This is different from dragging a part into an assembly:

  1. When you drag a part into another part you will get the above message:
  2. Now when you choose yes you will get the "Insert Part" Property Manager where you can define which geometry should be inserted into the receiving part:
  3. Depending on your selections you will get different results but you will always get a "feature" in the receiving part that shows you what you have inserted:

    We keep the inserted geometry in different folders so that you can comprehend why the entities are listed.

  4. This will create a geometrical copy of the design library part and you can add features on top of the inserted geometry.

 

Possible workflows are that you have i.e. a generic stock component that gets individually modified based on i.e. customer requirements.  Imagine a valve housing that is always identical but based on customer requirements it will get individual holes.

 

Whereas when you insert the design library part into an assembly you won't see this message and you can apply the different methods to make the part independent mentioned earlier.

 

Kind regards

Frank

SOLIDWORKS Product Definition Team

By: Frank Ruepp  Fri, 21 Apr 2017 15:32:32 GMT
Re: How to drag an un-linked part copy from design library?

Frank,

That does help make it clearer as to what is happening and what to choose. If I select no I get an extruded feature that can be edited and does not change the original part.

         One other example for selecting a derived part would be for machining a part. I could place a cast or welded part in a new part and then add the machining steps to get a new part for the finished product. This has potential.

 

Thank you

By: Jim Steinmeyer  Fri, 21 Apr 2017 15:47:53 GMT
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